Chapter 8: Partial Tip Clearance

This tutorial includes:

This tutorial teaches you how to:

As you work through this tutorial, you will create a mesh for an inlet guide vane that has partial tip clearance.

You will model partial tip clearance using the complex blade end feature, which is implemented using high-fidelity geometry.

Meshing with high-fidelity geometry involves a hybrid meshing approach, with blocks of unstructured meshes surrounding high-fidelity geometric features and blocks of structured meshes filling the remainder of the blade passage.

If this is the first tutorial you are working with, it is important to review Introduction to the Ansys TurboGrid Tutorials before beginning.

 

8.1. Preparing the Working Directory

  1. Create a working directory.

    Ansys TurboGrid uses a working directory as the default location for loading and saving files for a particular session or project.

  2. Download the guide_vane.zip file here .

  3. Unzip guide_vane.zip to your working directory.

    Ensure that the following tutorial input files are in your working directory:

    • InletGuideVane.tginit

    • InletGuideVane.tin

  4. Set the working directory and start Ansys TurboGrid.

    For details, see Setting the Working Directory and Starting Ansys TurboGrid.

 

8.2. Defining the Geometry

Load the geometry:

  1. Click File > Load TurboGrid Init File.

  2. Open InletGuideVane.tginit from the working directory.

Associate CAD objects with complex blade end topology in TurboGrid’s Geometry workspace as follows:

  1. In the Geometry workspace, expand the tree under Topological Entity Instances > Blade Set > IGV and note that the inlet guide vane, IGV, is defined by a set of topological entities with CAD geometry already assigned.

  2. Right-click IGV and select Insert Complex Blade End.

    A new topological entity, ComplexBladeEnd, appears in the tree as a child of IGV. If you expand the tree below ComplexBladeEnd you will see three child objects:

    • HighFidelityBladeSurface

    • HighFidelityHubSurface

    • HighFidelityShroudSurface

  3. Using the table below as a guide, assign CAD families, which are listed in the tree within the CAD Families branch, to the child objects of ComplexBladeEnd.

    To do this, for each child object of ComplexBladeEnd, double-click the child object to edit it in the object editor, then click CAD Entity Selector   beside the Location setting, then, in the CAD Region Entities dialog box, select the appropriate CAD family (or select multiple CAD families using Shift/Ctrl) and click OK, then, in the object editor, click Apply.

    Note:  An alternative method for assigning CAD families is to, for each child object of ComplexBladeEnd, in the object selector, select the appropriate CAD family (or select multiple CAD families using Shift/Ctrl) and use the Assign Family To Topology Instance shortcut menu command.

    Topological Entity

    CAD Families

    HighFidelityBladeSurface

    BLADEHUBTIP, BLADESHROUDTIP, DETAILEDBLADE

    HighFidelityHubSurface

    DETAILEDHUB

    HighFidelityShroudSurface

    DETAILEDSHROUD

This completes the geometry definition.

 

8.3. Creating the Topology and Mesh

In preparation for generating a mesh that conforms to a high-fidelity geometric feature, in this case complex blade ends, you will enable ATM3D.

  1. In the Mesh workspace, open Topology Set.

  2. Set Mesh Generation Mode to ATM3D.

  3. Click Apply.

  4. Right-click Topology Set and turn off Suspend Object Updates.

    After some time, you will see a warning message about the inlet and outlet domains being turned off.

  5. Dismiss the warning message.

The topology and 3D mesh are generated.

There is a pair of toolbar icons for selecting the type of geometry, high-fidelity or low-fidelity, for which to generate a mesh. Only one icon appears at a time. If the icon displayed in the toolbar is Use Mesh for Low-Fidelity Geometry   then high-fidelity geometry is selected for meshing, and clicking the icon would switch to low-fidelity geometry for meshing. The converse icon is Use Mesh for High-Fidelity Geometry  .

The Display menu contains a pair of commands that correspond to the icons. These commands and icons affect any existing mesh, any mesh subsequently generated, and any mesh subsequently saved.

  • Ensure that the toolbar icon is Use Mesh for Low-Fidelity Geometry   so that the meshing of high-fidelity geometry is enabled (and would be disabled by clicking the icon). Note that the icon text appears in the lower-left corner of the user interface.

 

8.4. Reviewing the Complex Blade End Objects in the Mesh Workspace

The Mesh workspace holds several objects related to the complex blade ends.

  1. Under Geometry > Blade Set, expand IGV and note that there is a Complex Blade End object.

    The IGV object shows the low-fidelity geometry, which does not feature complex blade ends.

    The Complex Blade End object shows the high-fidelity geometry, which features complex blade ends.

    You can toggle the visibility check boxes of these objects independently. Note that the child objects of Complex Blade End each have their own visibility check box.

    The Complex Blade End object can be edited to adjust the Topology Connection Tolerance settings, which indicate the distance(s) within which separate parts of the geometry should be topologically connected.

  2. Expand Mesh Data and note the IGV Hub Complex Blade End and IGV Shroud Complex Blade End objects.

    The visibility check boxes for these objects control the display of lines/surfaces on the geometry that indicate the boundaries of the unstructured meshes near the complex blade ends.

    The shortcut menus for these objects contain rendering commands that affect what is displayed; these commands can be used to help visualize problems with the CAD geometry, such as unwanted holes in the surface.

    The object editors for these objects contain settings that control the meshing of the complex blade ends.

    On the High-Fidelity Geometry tab:

    • The Enable High-Fidelity Feature check box provides a way to effectively ignore the applicable complex blade end feature when generating a mesh. You might want to do this to save computational time in some cases.

      When this check box is selected, the applicable complex blade end can affect the mesh and will affect the mesh provided that the global control (in the Display menu and in the toolbar) for geometric fidelity is set to enable high-fidelity geometry.

      When this check box is cleared, the applicable complex blade end is ignored during mesh generation, regardless of the global control setting.

    • Feature Refinement Factor controls the overall number of mesh elements used in the mesh near the applicable complex blade end.

    • Growth Rate controls how quickly the element size changes with respect to distance from a nearby wall in the mesh near the applicable complex blade end. This setting affects boundary layer discretization and indirectly affects the number of mesh elements used in the mesh near the applicable complex blade end.

    • Inflation Layer Mode controls whether the growth rate employed for each wall location is equal to, or allowed to vary from, the specified Growth Rate. The Constant Expansion option employs, for each wall location, the specified growth rate. The Last Aspect Ratio option employs, for each wall location, a growth rate based on the specified value but modified as needed to achieve a smooth transition in cell aspect ratio where the outermost inflation layer interfaces with the interior mesh.

    On the Complex Blade End tab:

    • Span Location is the normalized span location that approximately bounds the mesh for the complex blade end. The actual boundary is the nearest constant-K surface in the structured mesh, with an integer value of variable K.

    • Elements Per Gap applies to the unstructured mesh near the complex blade end and controls the number of elements used in close proximity to gaps.

    • Edge Length Refinement Factor controls mesh refinement at feature edges and can vary from 0 to 1, with 0 tending towards a coarse mesh and 1 tending towards a fine mesh.

    • The Inflation Layer Count Factors settings control, within the unstructured mesh block for the complex blade end, the number of inflation layers off the blade or wall as per the setting name: Blade, Hub, or Shroud.

    • The Named Selections to Join in Mesh settings create named selections that might be required, depending on the case, to generate the unstructured mesh block for the complex blade end.

    • The Tip Shell Selection Options settings affect the extent of the tip shell, which is the interface between the structured hex mesh of the passage and the unstructured mesh block for the complex blade end. If necessary, you can extend the tip shell so that it fully encompasses the high-fidelity geometric features of the complex blade end.

    The Mesh Data object contains additional settings that affect the unstructured meshes near the complex blade ends. These settings are found on the Hub Complex Blade End and/or Shroud Complex Blade End tabs, which are available when applicable.

  3. Expand 3D Mesh and note that there are several mesh objects available for viewing the mesh associated with the complex blade ends.

    Figure 8.1: Mesh on Blade and Hub Surfaces shows the following 3D Mesh objects near the blade leading edge: IGV_Hub_Complex_Blade_End_blade and IGV_Hub_Complex_Blade_End_wall. In this figure, the visibilities of other objects have been turned off for an unobstructed view.

    Figure 8.1: Mesh on Blade and Hub Surfaces

    Mesh on Blade and Hub Surfaces

 

8.5. Analyzing the Mesh

Check the 3D mesh statistics:

  1. Open Mesh Analysis.

    Some of the mesh statistics have apparent problems based on the current quality criteria. However, if you double-click any of the statistics that indicate a problem, you will see in the 3D Viewer that the indicated elements are related to the unstructured mesh near the blade tips. The quality criteria should ideally be different for the unstructured mesh, which in this case will work without any significant issues in a CFD solver. For example, even in a good unstructured mesh, the minimum face angle will typically fall below 5 degrees in some places.

  2. Close the Mesh Statistics dialog box.

 

8.6. Saving the Mesh

When you save a mesh, the resulting saved mesh reflects either the high-fidelity geometry or the low-fidelity geometry, whichever is currently set.

Save the mesh:

  1. Click File > Save Mesh As.

  2. Ensure that Files of type is set to Ansys CFX Mesh Files.

  3. Set Export Units to cm.

  4. Set File name to inlet_guide_vane.gtm.

  5. Ensure that your working directory is set correctly.

  6. Click Save.

 

8.7. Saving the State (Optional)

If you want to revisit this mesh at a later date, save the state:

  1. Click File > Save State As.

  2. Enter an appropriate state filename.

  3. Click Save.